Presentation is loading. Please wait.

Presentation is loading. Please wait.

Lathe Cutter Workshop 2A Stress Analysis. Workshop Supplement January 20, 2001 Inventory #001442 W2-2 2A. Stress Analysis Lathe Cutter Description Solve.

Published byGerard Benson Modified over 8 years ago

Similar presentations

Presentation on theme: "Lathe Cutter Workshop 2A Stress Analysis. Workshop Supplement January 20, 2001 Inventory #001442 W2-2 2A. Stress Analysis Lathe Cutter Description Solve."— Presentation transcript:

1 Lathe Cutter Workshop 2A Stress Analysis

2 Workshop Supplement January 20, 2001 Inventory #001442 W2-2 2A. Stress Analysis Lathe Cutter Description Solve a 3-D stress analysis of the lathe cutter model below. Review the results in the general postprocessor by: 1) plotting the displacements 2) listing reaction forces 3) plotting the von Mises stress 4) animating the von Mises stress Resolve the solution using a different set of constraints and compare the stress results to the first solution.

3 Workshop Supplement January 20, 2001 Inventory #001442 W2-3 2A. Stress Analysis Lathe Cutter Loads and Material Properties for the first solution:

4 Workshop Supplement January 20, 2001 Inventory #001442 W2-4 2A. Stress Analysis Lathe Cutter Loads and Material Properties for the second solution:

5 Workshop Supplement January 20, 2001 Inventory #001442 W2-5 2A. Stress Analysis Lathe Cutter 1.Enter ANSYS in the working directory specified by your instructor using “cutter” as the jobname. 2.Set the GUI Preferences to Structural: –Main Menu > Preferences … Select “Structural”, then [OK]

6 Workshop Supplement January 20, 2001 Inventory #001442 W2-6 2A. Stress Analysis Lathe Cutter 3.Import the “cutter.igs” IGES file using the “No defeaturing” option: –Utility Menu > File > Import > IGES … Select “No defeaturing”, then [OK] Select “cutter.igs’, then [OK] –Or issue: /AUX15 IOPTN,IGES,NODEFEAT IGESIN,cutter,igs,

7 Workshop Supplement January 20, 2001 Inventory #001442 W2-7 2A. Stress Analysis Lathe Cutter 4.Scale the model by converting centimeters to inches: –Main Menu > Preprocessor > Operate > Scale > Volumes + [Pick All] –Enter 1/2.54 for RX, RY, and RZ –Set IMOVE to “Moved”, then [OK] –Or issue: VLSCAL, ALL,,, 1/2.54, 1/2.54, 1/2.54,, 0, 1 –Utility Menu > Plot > Volumes –Or issue: VPLOT

8 Workshop Supplement January 20, 2001 Inventory #001442 W2-8 2A. Stress Analysis Lathe Cutter 5.Read input from “cutter-area.inp” to create a small area for applying pressure load at tip: –Utility Menu > File > Read Input from … Select “cutter-area.inp”, then [OK] –Or issue: /INPUT,cutter-area,inp

9 Workshop Supplement January 20, 2001 Inventory #001442 W2-9 2A. Stress Analysis Lathe Cutter 6.Specify the element type: –Main Menu > Preprocessor > Element Type > Add/Edit/Delete … [Add...] –Select “Structural Solid” and “Tet 10node 92”, then [OK] [Close] –Or issue: ET,1,SOLID92

10 Workshop Supplement January 20, 2001 Inventory #001442 W2-10 2A. Stress Analysis Lathe Cutter 7.Define elastic modulus for material 1 to be 10e6 (Aluminum): –Main Menu > Preprocessor > Material Props > Material Models … Structural -> Linear -> Elastic -> Isotropic Set EX = 10e6 (Young’s modulus in psi for Aluminum) Set PRXY =.32 [OK] Select Material > Exit –Or issue: MP,EX,1,10e6 MP,PRXY,1,.32

11 Workshop Supplement January 20, 2001 Inventory #001442 W2-11 2A. Stress Analysis Lathe Cutter 8.Activate smartsize meshing and mesh the model with tetrahedral elements: –Main Menu > Preprocessor > MeshTool … Activate “Smart Size” Set Smart Size level to 4 [Mesh] [Pick All] [Close] –Or issue: SMRT,4 MSHAPE,1,3D MSHKEY,0 VMESH

12 Workshop Supplement January 20, 2001 Inventory #001442 W2-12 2A. Stress Analysis Lathe Cutter 9.Apply area “symmetry” constraint to restrain attachment region: –Utility Menu > Plot > Areas –Main Menu > Solution > -Loads- Apply > -Structural- Displacement > -Symmetry B.C.- On Areas + Pick areas 18, 19, 25, and 26, then [OK] –Or issue: DA,18,SYMM DA,19,SYMM DA,25,SYMM DA,26,SYMM

13 Workshop Supplement January 20, 2001 Inventory #001442 W2-13 2A. Stress Analysis Lathe Cutter 10.Apply pressure load at tip: –Main Menu > Solution > -Loads- Apply > -Structural- Pressure > On Areas + Pick area 1, then [OK] VALUE = 10000 [OK] –Or issue: SFA,1,1,PRES,10000

14 Workshop Supplement January 20, 2001 Inventory #001442 W2-14 2A. Stress Analysis Lathe Cutter 11.Save the database and obtain the solution: –Click the “SAVE_DB” button in the Toolbar (or select: Utility Menu > File > Save as Jobname.db) –Main Menu > Solution > -Solve- Current LS Review the “/STATUS Command” window and then close it [OK] [Close] - to close the yellow message window after the solution is completed –Or issue: /SOLU SOLVE

15 Workshop Supplement January 20, 2001 Inventory #001442 W2-15 2A. Stress Analysis Lathe Cutter 12.Review the results: 12a. Plot displacements: –Main Menu > General Postproc > Plot Results > -Contour Plot- Nodal Solu... Select “DOF solution” and “Translation USUM”, select “Def + undef edge”, then [OK] –Or issue: /POST1 PLNSOL,U,SUM,2,1

16 Workshop Supplement January 20, 2001 Inventory #001442 W2-16 2A. Stress Analysis Lathe Cutter

17 Workshop Supplement January 20, 2001 Inventory #001442 W2-17 2A. Stress Analysis Lathe Cutter 12b. List reaction forces: –Main Menu > General Postproc > List Results > Reaction Solu... Select “All items”, then [OK] –Or issue: PRRSOL

18 Workshop Supplement January 20, 2001 Inventory #001442 W2-18 2A. Stress Analysis Lathe Cutter

19 Workshop Supplement January 20, 2001 Inventory #001442 W2-19 2A. Stress Analysis Lathe Cutter 12c. Plot von Mises stress: –Main Menu > General Postproc > Plot Results > -Contour Plot- Nodal Solu... Select “Stress” and “von Mises SEQV”, then [OK] –Or issue: PLNSOL,S,EQV

20 Workshop Supplement January 20, 2001 Inventory #001442 W2-20 2A. Stress Analysis Lathe Cutter 12d. Capture the image then minimize : –Utility Menu > Plot Cntrls > Capture Image –Minimize the window for later comparison

21 Workshop Supplement January 20, 2001 Inventory #001442 W2-21 2A. Stress Analysis Lathe Cutter 12e. Animate the von Mises stress: –Utility Menu > PlotCtrls > Animate > Deformed Results... Select “Stress” and “von Mises SEQV”, then [OK] –Or issue: PLNSOL,S,EQV ANCNTR,10,0.5

22 Workshop Supplement January 20, 2001 Inventory #001442 W2-22 2A. Stress Analysis Lathe Cutter

23 Workshop Supplement January 20, 2001 Inventory #001442 W2-23 2A. Stress Analysis Lathe Cutter 13.Close the animation and delete the area symmetry constraints: [Close] –Utility Menu > Plot > Areas –Main Menu > Solution > -Loads- Delete > -Structural- Displacement > On Areas + Pick areas 18, 19, 25, and 26, then [OK] [OK] –Or issue: DADELE,18,ALL DADELE,19,ALL DADELE,25,ALL DADELE,26,ALL 14.Apply “ALL DOF” constraint to areas 18, 19, and 26: –Main Menu > Solution > -Loads- Apply > -Structural- Displacement > On Areas + Pick areas 18, 19, and 26, then [OK] Select “All DOF”, then [OK] –Or issue: DA,18,ALL DA,19,ALL DA,26,ALL

24 Workshop Supplement January 20, 2001 Inventory #001442 W2-24 2A. Stress Analysis Lathe Cutter 15. Change the title: –Utility Menu > File > Change Title … Type in the title: Lathe Cutter - with ALL DOF constraint on areas at hole [OK] 16.Save the database and obtain the solution: –Pick the “SAVE_DB” button in the Toolbar (or select: Utility Menu > File > Save as Jobname.db) –Main Menu > Solution > -Solve- Current LS [OK] [Close] –Or issue: SAVE /SOLU SOLVE 17.Review the results: –Main Menu > General Postproc > Plot Results > -Contour Plot- Nodal Solu... Select “Stress” and “von Mises SEQV” [OK] –Or issue: PLNSOL,S,EQV

25 Workshop Supplement January 20, 2001 Inventory #001442 W2-25 2A. Stress Analysis Lathe Cutter Open minimized plot from previous analysis to compare results

26 Workshop Supplement January 20, 2001 Inventory #001442 W2-26 2A. Stress Analysis Lathe Cutter 17.Save and exit ANSYS: –Pick the “QUIT” button from the Toolbar (or select: Utility Menu > File > Exit...) Select “Save Everything” [OK] –Or issue: FINISH /EXIT,ALL

27 2-D Corner Bracket Tutorial Workshop 2B Stress Analysis

28 Workshop Supplement January 20, 2001 Inventory #001442 W2-28 2B. Stress Analysis 2-D Corner Bracket Tutorial Description This workshop introduces you to ANSYS tutorials — solved, step-by-step examples that are available on-line in HTML format. The problem consists of a static analysis of a corner bracket modeled with 2-D plane stress elements.

29 Workshop Supplement January 20, 2001 Inventory #001442 W2-29 2B. Stress Analysis 2-D Corner Bracket Tutorial 1.Enter ANSYS in the working directory specified by your instructor using “bracket” as the jobname. 2.Access the ANSYS on-line tutorials: –Utility Menu > Help > ANSYS Tutorials Open the “Structural Tutorial” folder Select the “Static Analysis of a Corner Bracket” folder Perform steps 1 through 26 –Or issue the following path in your browser’s “Go to:” window: Unix: \ansys57\docu\english\ansyshelp\Hlp_UI_Tutorials.html Intel-PC: D:/ansys57/docu/english/tuthelp.chm (Note, ask your instructor for the path name on your machine that points to the TUTORToc.htm file)

30

Download ppt "Lathe Cutter Workshop 2A Stress Analysis. Workshop Supplement January 20, 2001 Inventory #001442 W2-2 2A. Stress Analysis Lathe Cutter Description Solve."

Similar presentations

ANSYS Model of a Cylindrical Fused Silica Fibre

ANSYS Model of a Cylindrical Fused Silica Fibre
Results Viewer Workshop 13D Postprocessing. Workshop Supplement November 1, 2002 Inventory #001756 W13-2 13D. Postprocessing Results Viewer Description.

Results Viewer Workshop 13D Postprocessing. Workshop Supplement November 1, 2002 Inventory # W D. Postprocessing Results Viewer Description.
Building Frame Workshop 4 Beam Modeling. Workshop Supplement October 30, 2001 Inventory #001572 W4-2 4. Beam Modeling Building Frame Determine the deflections.

Building Frame Workshop 4 Beam Modeling. Workshop Supplement October 30, 2001 Inventory # W Beam Modeling Building Frame Determine the deflections.
WS11-1 VND101, Workshop 11 MSC.visualNastran 4D Exercise Workbook Bracket.

WS11-1 VND101, Workshop 11 MSC.visualNastran 4D Exercise Workbook Bracket.
3-D Bracket Workshop 10A Loading and Solution. Workshop Supplement February 7, 2006 Inventory #002269 W10-2 10A. Loading and Solution 3-D Bracket Description.

3-D Bracket Workshop 10A Loading and Solution. Workshop Supplement February 7, 2006 Inventory # W A. Loading and Solution 3-D Bracket Description.
Module 5 Beam Modeling.

Module 5 Beam Modeling.
Swaybar-Shaft Assembly Workshop 8 Bonded Contact.

Swaybar-Shaft Assembly Workshop 8 Bonded Contact.
Bolt Torque Workshop 3 Surface Effect Elements. Workshop Supplement October 30, 2001 Inventory #001572 W3-2 3. Surface Effect Elements Bolt Torque Description.

Bolt Torque Workshop 3 Surface Effect Elements. Workshop Supplement October 30, 2001 Inventory # W Surface Effect Elements Bolt Torque Description.
Finite Element Method FEM Dr. Mohammed Al-Hazmi ANSYS Basics Lecture 4.

Finite Element Method FEM Dr. Mohammed Al-Hazmi ANSYS Basics Lecture 4.
Thermal Analysis Module 6. Training Manual January 30, 2001 Inventory #001441 6-2 Thermal Analysis In this chapter, we will briefly describe the procedure.

Thermal Analysis Module 6. Training Manual January 30, 2001 Inventory # Thermal Analysis In this chapter, we will briefly describe the procedure.
Module 7 Modal Analysis.

Module 7 Modal Analysis.
Verifying Pressures Workshop 9 Macro Basics. Workshop Supplement October 30, 2001 Inventory #001572 W9-2 9. Macro Basics Verifying Pressures Create a.

Verifying Pressures Workshop 9 Macro Basics. Workshop Supplement October 30, 2001 Inventory # W Macro Basics Verifying Pressures Create a.
9.0 New Features Large Deformation Analysis of thin plate assembly spotwelded together Workshop 2 Spotwelds.

9.0 New Features Large Deformation Analysis of thin plate assembly spotwelded together Workshop 2 Spotwelds.
ANSYS Fundamentals This document contains no technical data subject to the EAR or the ITAR.

ANSYS Fundamentals This document contains no technical data subject to the EAR or the ITAR.
Large Deflection Arched Beam Workshop 7 Nonlinear Analysis.

Large Deflection Arched Beam Workshop 7 Nonlinear Analysis.
University of Puerto Rico at Mayagüez Department of Mechanical Engineering Introduction to NX 6.0 Tutorial 1 Modified by (2011): Dr. Vijay K. Goyal and.

University of Puerto Rico at Mayagüez Department of Mechanical Engineering Introduction to NX 6.0 Tutorial 1 Modified by (2011): Dr. Vijay K. Goyal and.
Problem 2: Thermal Solidification of a Casting University of Puerto Rico at Mayagüez Department of Mechanical Engineering Modified by (2008): Dr. Vijay.

Problem 2: Thermal Solidification of a Casting University of Puerto Rico at Mayagüez Department of Mechanical Engineering Modified by (2008): Dr. Vijay.
Workshop :Bicycle Frame Design Modified by (2009): Dr. Vijay K. Goyal Associate Professor, Department of Mechanical Engineering University of Puerto Rico.

Workshop :Bicycle Frame Design Modified by (2009): Dr. Vijay K. Goyal Associate Professor, Department of Mechanical Engineering University of Puerto Rico.
University of Puerto Rico at Mayagüez Department of Mechanical Engineering Introduction to NX 6.0 Tutorial 4 Modified by (2011): Dr. Vijay K. Goyal and.

University of Puerto Rico at Mayagüez Department of Mechanical Engineering Introduction to NX 6.0 Tutorial 4 Modified by (2011): Dr. Vijay K. Goyal and.
Workshop: Bicycle Frame Design Modified by (2009): Neysa A. Fuentes Department of Mechanical Engineering University of Puerto Rico, Mayagüez Jelisa Torres.

Workshop: Bicycle Frame Design Modified by (2009): Neysa A. Fuentes Department of Mechanical Engineering University of Puerto Rico, Mayagüez Jelisa Torres.

Similar presentations

Ads by Google